program.H 0 blocks

BEGIN PGM PROGRAM MM
;==================================================
; TNC SIM - DEMO PROGRAM
; Blank: 100 x 100 x 20 mm
; Contains: contour milling, drilling, reaming,
;           edge chamfering and thread tapping
;==================================================
BLK FORM 0.1 Z X-50 Y-50 Z+0
BLK FORM 0.2 X+50 Y+50 Z+20
;
;--------------------------------------------------
; T1 - End mill D16 (contour roughing)
; Mill outer contour down to 20mm depth
;--------------------------------------------------
TOOL CALL 1 Z S18000 F3500
TOOL DEF 3 ; Pre-load tool in magazine for next TOOL CALL
M3 ; Spindle ON — clockwise
M8 ; Coolant ON — flood
L X+0 Y+90 Z+50 FMAX R0
L X+0 Y+90 Z+0 F2000
L Y+100 RL ; activate left radius comp
CC X+0 Y+75 ; circle center for tangential entry arc
C X+0 Y+50 DR+ ; sweeps tangentially onto the contour (avoids a straight-plunge tool mark)
L X+50
RND R20 ; corner rounding
L Y-50
RND R20
L X-50
RND R20
L Y+50
RND R20
L X+10
CC X+10 Y+75 ; circle center for tangential exit arc
C X+10 Y+100 DR+ ; sweeps tangentially off the contour
L Z+100 FMAX R0
; Mill central circular pocket D20
CYCL DEF 208 ;Circular Pocket Milling
  Q200=+2 ;Safety clearance [mm]
  Q201=-20 ;Depth [mm]
  Q206 FAUTO ;Feed rate - plunge [mm/min]
  Q334=+2 ;Infeed per pass [mm]
  Q203=+20 ;Surface coordinate [mm]
  Q204=+50 ;2nd safety clearance [mm]
  Q335=+20 ;Nominal diameter [mm]
  Q342=+0 ;Pre-drilled dia. [mm]
  Q351=+1 ;Milling mode
  Q370=+1 ;Path overlap factor
L X+0 Y+0 FMAX M99
M5 ; Spindle OFF
M9 ; Coolant OFF
;
;--------------------------------------------------
; T3 - Center drill D8 (spot drill hole centers)
; LBL 1 = right holes, LBL 2 = left holes
;--------------------------------------------------
TOOL CALL 3 Z S18000 F300
TOOL DEF 4 ; Pre-load tool in magazine for next TOOL CALL
M3 ; Spindle ON — clockwise
M8 ; Coolant ON — flood
CYCL DEF 200 ;Drilling
  Q200=+2 ;Safety clearance [mm]
  Q201=-1 ;Depth [mm]
  Q206=+150 ;Feed rate - plunge [mm/min]
  Q202=+1 ;Plunging depth [mm]
  Q210=+0 ;Dwell time at top [s]
  Q203=+20 ;Surface coordinate [mm]
  Q204=+50 ;2nd safety clearance [mm]
  Q211=+0 ;Dwell time at depth [s]
LBL 1
; hole positions for reaming 7H7
L X+30 Y+30 FMAX R0 M99
L X+30 Y-30 FMAX R0 M99
LBL 0
LBL 2
; hole positions for M8 thread
L X-30 Y-30 FMAX R0 M99
L X-30 Y+30 FMAX R0 M99
LBL 0
M5 ; Spindle OFF
M9 ; Coolant OFF
;
;--------------------------------------------------
; T4 - Drill D7 (drill before reaming and tapping)
; depth 24mm through full blank + breakthrough
;--------------------------------------------------
TOOL CALL 4 Z S14000 F300
TOOL DEF 5 ; Pre-load tool in magazine for next TOOL CALL
M3 ; Spindle ON — clockwise
M8 ; Coolant ON — flood
CYCL DEF 200 ;Drilling
  Q200=+2 ;Safety clearance [mm]
  Q201=-24 ;Depth [mm]
  Q206 FAUTO ;Feed rate - plunge [mm/min]
  Q202=+11.5 ;Plunging depth [mm]
  Q210=+0 ;Dwell time at top [s]
  Q203=+20 ;Surface coordinate [mm]
  Q204=+50 ;2nd safety clearance [mm]
  Q211=+0 ;Dwell time at depth [s]
CALL LBL 1 ; drill right holes
CALL LBL 2 ; drill left holes
M5 ; Spindle OFF
M9 ; Coolant OFF
;
;--------------------------------------------------
; T5 - Chamfer / countersink 90deg D8
; DL-2 DR+2 = tip offset for 1x45deg chamfer
; Chamfer all hole edges with cycle 208
;--------------------------------------------------
TOOL CALL 5 Z S18000 F1000 DL-2 DR+2
TOOL DEF 6 ; Pre-load tool in magazine for next TOOL CALL
M3 ; Spindle ON — clockwise
M8 ; Coolant ON — flood
L X+0 Y+90 Z+50 FMAX R0
L X+0 Y+90 Z+19 F2000
L Y+100 RL
CC X+0 Y+75 ; circle center for tangential entry arc
C X+0 Y+50 DR+ ; sweeps tangentially onto the contour (avoids a straight-plunge tool mark)
L X+50
RND R20
L Y-50
RND R20
L X-50
RND R20
L Y+50
RND R20
L X+10
CC X+10 Y+75 ; circle center for tangential exit arc
C X+10 Y+100 DR+ ; sweeps tangentially off the contour
L Z+100 FMAX R0
; Chamfer edge of central hole D20
CYCL DEF 208 ;Circular Pocket Milling
  Q200=+2 ;Safety clearance [mm]
  Q201=-1 ;Depth [mm]
  Q206 FAUTO ;Feed rate - plunge [mm/min]
  Q334=+0 ;Infeed per pass [mm]
  Q203=+20 ;Surface coordinate [mm]
  Q204=+50 ;2nd safety clearance [mm]
  Q335=+20 ;Nominal diameter [mm]
  Q342=+19.9999 ;Pre-drilled dia. [mm]
  Q351=+1 ;Milling mode
  Q370=+1 ;Path overlap factor
L X+0 Y+0 FMAX M99
; Chamfer edges of D7 holes (reaming)
CYCL DEF 208 ;Circular Pocket Milling
  Q200=+2 ;Safety clearance [mm]
  Q201=-1 ;Depth [mm]
  Q206=+150 ;Feed rate - plunge [mm/min]
  Q334=+0 ;Infeed per pass [mm]
  Q203=+20 ;Surface coordinate [mm]
  Q204=+50 ;2nd safety clearance [mm]
  Q335=+7 ;Nominal diameter [mm]
  Q342=+6.999 ;Pre-drilled dia. [mm]
  Q351=+1 ;Milling mode
  Q370=+1 ;Path overlap factor
CALL LBL 1
; Chamfer edges of D8 holes (thread)
CYCL DEF 208 ;Circular Pocket Milling
  Q200=+2 ;Safety clearance [mm]
  Q201=-1 ;Depth [mm]
  Q206=+150 ;Feed rate - plunge [mm/min]
  Q334=+0 ;Infeed per pass [mm]
  Q203=+20 ;Surface coordinate [mm]
  Q204=+50 ;2nd safety clearance [mm]
  Q335=+8 ;Nominal diameter [mm]
  Q342=+7.999 ;Pre-drilled dia. [mm]
  Q351=+1 ;Milling mode
  Q370=+1 ;Path overlap factor
CALL LBL 2
M5 ; Spindle OFF
M9 ; Coolant OFF
;
;--------------------------------------------------
; T6 - Reamer D7 H7 (precision ream holes)
; right holes only (LBL 1)
;--------------------------------------------------
TOOL CALL 6 Z S12200 F300
TOOL DEF 7 ; Pre-load tool in magazine for next TOOL CALL
M3 ; Spindle ON — clockwise
M8 ; Coolant ON — flood
CYCL DEF 201 ;Reaming
  Q200=+2 ;Safety clearance [mm]
  Q201=-22 ;Depth [mm]
  Q206 FAUTO ;Feed rate - reaming [mm/min]
  Q211=+0 ;Dwell time at depth [s]
  Q208=+0 ;Retraction feed rate [mm/min]
  Q203=+20 ;Surface coordinate [mm]
  Q204=+50 ;2nd safety clearance [mm]
CALL LBL 1
M5 ; Spindle OFF
M9 ; Coolant OFF
;
;--------------------------------------------------
; T7 - Tap M8 (thread tapping with chip breaking)
; Q257=11 step depth, Q256=0 full retract out of the hole
; left holes only (LBL 2)
;--------------------------------------------------
TOOL CALL 7 Z S350
M3 ; Spindle ON — clockwise
M8 ; Coolant ON — flood
CYCL DEF 209 ;Tapping with Chip Breaking
  Q200=+2 ;Safety clearance [mm]
  Q201=-22 ;Thread depth [mm]
  Q239=+1.25 ;Thread pitch [mm]
  Q203=+20 ;Surface coordinate [mm]
  Q204=+50 ;2nd safety clearance [mm]
  Q257=+11 ;Infeed depth for chip breaking [mm]
  Q256=+0 ;Retract factor (x pitch; 0 = full retract)
  Q336=+0 ;Spindle angle [deg]
CALL LBL 2
M5 ; Spindle OFF
M9 ; Coolant OFF
END PGM PROGRAM MM

3D view

XY toolpath

Tool Table

Ready — press Run X: 0.000 Y: 0.000 Z: 0.000

Select Cycle

🐛 Report a bug or suggest an improvement ×

TNC Sim — Help ×

🐛 Report a bug or suggest an improvement

TNC Sim — Help